Sheet Metal Flat Length Calculator
Every bend eats a slice of length, so a folded part is always shorter than the sum of its outside dimensions. This tool computes bend allowance, bend deduction and the flat blank length from thickness, radius, K-factor and angle.
| Bend allowance BA (neutral-axis arc) | — mm |
| Bend deduction BD (per bend) | — mm |
| Shortening versus outside sum | — % |
| Neutral radius (r + K·t) | — mm |
Flat length is geometry, not an estimate: with thickness, radius and K-factor fixed, the answer is exact to 0.01 mm. The K-factor itself is empirical — it depends on material, die opening and bending method, and 0.05 of K moves a 100 mm leg by about 0.3 mm. Always confirm with a trial bend before a production run.
Three numbers people confuse
- Bend allowance (BA) — the arc the neutral axis travels through the bend, in radians: BA = θ × (r + K·t). This is the length the bend actually occupies on the part.
- Bend deduction (BD) — how much the sum of two outside dimensions exceeds the true flat length. For 90°, BD = 2(r + t) − BA.
- Flat length — outside dimensions summed, minus one deduction per bend. This is what you cut, nest and program.
Using BA where BD belongs is the classic shop-floor error: at 90° with r ≈ t they differ by more than 2×. Check whether the drawing dimensions are outside or inside — this tool assumes outside dimensions.
Formulas
BA = θ(rad) × (r + K·t)
BD = 2(r + t) × tan(θ/2) − BA
flat length = Σ outside dimensions − bends × BD
shortening % = (1 − flat ÷ outside sum) × 100 Worked example
2 mm cold-rolled sheet, inside R1, K = 0.33, two 90° bends, outside dimensions 100 + 100 + 100:
| BA = 1.5708 × (1 + 0.33×2) | 2.607 mm |
| BD = 2×3×1 − 2.607 | 3.392 mm |
| Total deduction = 2 × 3.392 | 6.785 mm |
| Flat length = 300 − 6.785 | 293.22 mm |
Cut 300 mm and every part comes out 6.8 mm long: the outside dimensions grow to about 101.7 mm per leg and every hole pattern shifts. On a 5,000-piece run that is 34 metres of wasted sheet before rework — far more than the cost of doing this arithmetic once.
Choosing a K-factor
K is where the neutral axis sits as a fraction of thickness. Thin sheet with a small radius puts it near the inside face (K ≈ 0.33); as the radius grows it migrates toward the middle (K → 0.5).
| r / t | Typical K | Case |
|---|---|---|
| 0.5 | 0.33 | 1–2 mm CRS, V-die ≈ 6t |
| 1.0 | 0.38 | Standard air bending |
| 2.0 | 0.42 | Aluminium, stainless, larger R |
| 3.0 | 0.45 | Thick sheet, big radius |
| ≥5 | 0.50 | Approaching pure bending |
Press brake, tooling and clamping style shift the real value by 0.02–0.05. The reliable method is a trial bend from the same coil: measure the gap between actual blank and outside sum, back-solve K, then cut the batch.
Why it matters for cost
Flat length drives material cost directly, and nesting utilisation depends on the blank outline. Feed this length into the sheet metal cost calculator together with the bend count to get a full material + cut + bend cost per part. Rework from a wrong blank appears in no model, yet it is the most common loss in a fabrication shop.
Not included
- Springback compensation for large radii, high-strength steel or aluminium
- Forming operations such as beads, draws and flanges
- Weld shrinkage on welded assemblies
- Mixed bend angles in one part — the tool assumes a single angle throughout
- Laser kerf compensation, normally handled by the nesting software
FAQ
Why not just add the outside dimensions?
Because material follows an arc through the bend: the outside is stretched, the inside compressed, and neither equals the square corner you measured. The sum of outside dimensions is always longer than the true flat, and the excess is the bend deduction. Thicker sheet, larger radius and more bends all widen the gap.
How do inside and outside dimensions relate?
The sum of inside dimensions is smaller by 2(r + t) per 90° bend. Convert to outside dimensions first, or work with inside dimensions minus BA — mixing the two conventions is the main cause of wrong blanks.
Does stainless use the same K-factor as aluminium?
No. Stainless has higher yield and more springback, so K runs slightly lower at the same r/t; aluminium's lower modulus makes springback more visible. A common practice is to subtract 0.02 from the table for stainless and 0.01 for aluminium, then correct with a trial bend.